If you take the example of an IC engine, the parameters are like piston, crank shaft and relation is like the connecting rod. Pro engineer parameters and relations help to keep the design intent intact. In this article we will see how to create and use parameters and relations in pro engineer.

- slide 1 of 2
**Relations**Pro engineer is highly parametric software, means if you edit any dimension to see the change in the model. Due to the parametric nature of pro engineer, relations could be added between different dimensions and parameters. Relations are basically some user written equations. Relations help modification of different dimensions and parameters in a predetermined proportion.

The relations equations may be some sort of simple equation or may be some comparison statement.

You can even use simultaneous equations and logical statement as part of relations.

**Operators used in relations:**The operators (and their purpose shown between parenthesis) you can use in pro engineer relations are as below:**Arithmetic operators:***+ (addition), - (subtraction), *(multiplication), ^ (exponentiation),/ (division),()(parenthesis).***Assignment operators:***= (equal to)***Comparison operator:**When a TRUE/FALSE kind of value is expected from a statement, then comparison operator is used. For example, if you want to know whether

**d32**is less than**d33**or not, you can use the statement like below:*If***d32<= d33****Functions used in relations:**Apart from almost all mathematical and trigonometric functions, you can use**graph evaluation function**for controlling dimension through a graph.**How to add relation in pro engineer model:**For adding relations, please follow**tools>relations**and you will get relation dialogue box. You have to type the relation in the box. For writing relations between different dimensions, you need to find the**dimensions names**instead of**dimensions text.**So you will click**info>switch dimensions**to toggle the dimensions text to dimensions names.**Example:**Suppose in a cylinder the diameter is represented by**d32**and height by**d33,**then the simplest for of relation may be**d32=d33**, by doing so whenever you will change diameter height also will be changed to become equal with diameter. In this case of relation**d33**is called driving dimension and**d32**is called driven dimension. You cannot change driven dimension manually (like normal editing).After adding a relation in relation dialog box you can check the correctness of the relation by clicking

**utilities>verify**of relation dialog box. - slide 2 of 2
**Parameters**Parameters are useful to provide information about the pro engineer model/assembly. Some of the parameters are system generated parameters and some are user defined parameters. We will discuss here about user defined parameters.

User defined parameters are useful for providing/tagging additional information with the pro engineer geometry. These parameters can be used in family table, relations, ProE BOM creation etc.

Lets take an example, Suppose you are modeling a plastic glass using pro engineer, you can add an additional user defined parameter like

, now after adding the parameter color, you can a create family table for different colored glasses. Going further by using relation you can vary the size of the glasses for different colors.*color*Click on

**tools>parameters**to open parameter dialog box and then go to**parameters>add parameters**to add user defined parameters. It will add one more row to the parameter dialog box, you have to rename the parameter, define the type, value and access of the parameter.**How to use parameters in family table?**Go to

**tools>family table**and then add a new column (item), it will open the**item selection dialog box**, there click on**parameter**and it will direct you to the**parameter dialog box**there you need to select the required parameter. Now the value of the parameter could be set from family table.**How to use parameters in relations?**As you already know how to create parameter and relation, so let’s answer this question win an example. Suppose you have a cylinder, whose diameter is represented by

**d45**and height by**d46.**Now if you want that the dimension**d46**should be controlled by a user defined parameter say, DIA, then you have to follow the below mentioned steps:- Create a parameter DIA.
- Put some value of the parameter (DIA), say, 15.
- Add a relation,
**d46=DIA** - Remember to regenerate to see the change.